Overview#
The Drawing workspace turns a 3D design into a 2D, manufacturing-ready document: orthographic views, sections, dimensions, notes, tables, and a title block on a sheet. A drawing is its own document in Fusion, separate from the design file, but it references the design. Change the model, and the views in the drawing can be updated to match.
Use a drawing when you need to hand a part to a machine shop, a laser or waterjet vendor, an inspector, or a customer who expects a paper or PDF print. If you only need CAM toolpaths or a 3D print, you do not need a drawing at all.
Key ideas before you start:
- A drawing document contains one or more sheets. Each sheet holds views, annotations, and tables.
- Every view is a view of a design (or of a saved animation/exploded state). Views are not editable geometry; you annotate them, you do not sketch the part in them.
- Drawing defaults (units, standard, text height, arrow style, sheet size, title block) come from a drawing template. See the templates page of this section.
- Dimensions you add in a drawing are reference dimensions that measure the model. They do not drive the model. To change a size, edit the 3D design.
Where to find it#
Autodesk's help lists several entry points, all of which open the Create Drawing dialog.
- From the Application bar. With a saved design open, choose File > New Drawing > From Design (or From Animation). The Workspace menu offers the same New Drawing command.
- From the Data Panel. Right-click a design and choose New Drawing From Design.
- From the browser. Right-click any component and choose Create Drawing; Contents is then set to Select with that component already chosen.
- File > New... and pick Drawing in the dialog.
The drawing opens in a new document tab. With the Manual drawing type, Fusion then prompts you to place a base view and associate it with a reference in the browser; with Automatic, sheets are generated from your automation preferences. Double-clicking an existing drawing also opens the Drawing workspace.
Inside the drawing document the Drawing tab of the toolbar is divided into nine panels:
| Panel | Commands (per Autodesk's Drawing workspace reference) |
|---|---|
| Create | Base View, Projected View, Section View, Detail View, Break View, Create Sketch; the dedicated help also documents Auxiliary View, Breakout Section View, Crop View and Perspective View. Base View Placeholder appears only in the Template environment |
| Modify | Move, Rotate, Delete |
| Geometry | Center Line, Center Mark, Center Mark Pattern, Edge Extension, Create Sketch |
| Dimensions | Dimension, Auto Dimension, Tidy Up, Ordinate, Linear, Aligned, Angular, Radius, Diameter, Jogged Radial, Arc Length, Curve Min Max, Baseline, Chain, Arrange Dimensions, Match Dimension, Flip Arrows, Dimension Break |
| Text | Text, Note, Leader, Hole and Thread Note, Bend Note |
| Symbols | Surface Texture, Feature Control Frame, Datum Identifier, Welding, Taper and Slope, Edge Symbol, Sketch Symbol |
| Insert | Image |
| Tables | Table (parts list, hole table, revision history, bend table, custom table), Balloon, Bend Identifier, Renumber, Align Balloon |
| Export | Export PDF, Export DWG, Export Sheet as DXF, Export CSV |
Sheets are managed in the Sheet Bar at the bottom of the canvas, not on the toolbar.
Step by step#
- Save your design and give it a meaningful name. The drawing references the design file.
- With the design open choose File > New Drawing > From Design (or right-click the design in the Data Panel and choose New Drawing From Design).
- In Create Drawing, choose the Drawing Type (Manual to place views yourself), the Contents (Full Assembly, Visible Only or Select), the Destination (new or existing drawing, From Scratch or a Template), Standard (ASME or ISO), Units (in or mm), Sheet Size (ISO A4-A0 or ASME A-E, plus Custom) and Orientation (Landscape or Portrait).
- Click OK. The drawing opens in a new tab and prompts you to place a base view and associate it with a reference.
- In the Drawing View dialog choose Orientation (for example Front), Scale, Style (Visible Edges, Visible Edges and Hidden Edges, Shaded, Shaded with Hidden Edges) and place the view on the sheet.
- Click OK to finish the base view. Use Projected View to add further views.
- Add dimensions, centerlines, notes, tables, and balloons. See the following pages.
- Save the drawing (Ctrl+S). It saves as its own document next to the design.
- Export a PDF or DWG when ready.
Drawing from an animation#
Choose New Drawing > From Animation and pick a Storyboard in the Create Drawing dialog (created in the Animation workspace). This is how you get an exploded assembly view with balloons. The details are covered in the sheets-and-exploded page.
Options reference#
Create Drawing dialog:
| Option | What it does | Notes/default |
|---|---|---|
| Drawing Type | Automatic generates sheets from your automation preferences; Manual lets you place views yourself | |
| Contents (From Design) | Full Assembly, Visible Only, or Select | Visible Only follows the visibility icons in the browser |
| Representation (sheet metal only) | Folded Model or Flat Pattern | Decides which state the views use |
| Storyboard (From Animation) | Which storyboard to draw | |
| Drawing | Create New, or Browse to an existing drawing | An existing drawing can receive a new sheet or be added to an existing sheet |
| Base Document | From Scratch (default blank template) or a Template | A template carries title blocks, borders, settings and placeholders |
| Standard | ASME or ISO | Read-only after creation |
| Units | in or mm | Read-only after creation |
| Sheet Size | ISO A4 to A0 (297 x 210 mm up to 1189 x 841 mm); ASME A to E (11 x 8.5 in up to 44 x 34 in); Custom | Custom width and height are limited to 200 in or 5000 mm |
| Orientation | Landscape or Portrait | |
| Sheet Count | Number of sheets to generate | Default 1 |
| Sheet Creation (Automatic only) | First Level or All Level | All Level makes a sheet for every component |
| Open Drawing After Generation (Automatic only) | Opens the generated drawing in a new tab |
Tip: Standard and units are read-only in Document Settings once the drawing exists (Autodesk: they can only be specified when you first create a drawing), so choose them deliberately here and pick the right template at creation.
Understanding the design link#
- A drawing references the design. When the design is saved with changes the drawing is out of date, which Autodesk indicates with a Get Latest button on the toolbar. Click it to update the active sheet; other sheets are greyed out until you view them, and PDF and DWG export is blocked until every sheet is up to date.
- Dimensions and annotations stay attached to model edges. If an annotation loses its geometry, an Annotation Monitor badge appears; click it to Reassociate or delete the annotation. Exporting with disassociated annotations gives an error.
- If you open a drawing and cannot find the model, check that the design has not been moved, renamed, or deleted.
- Drawings of assemblies show each component; components with the same geometry appear in the parts list with quantities.
Navigation and display#
Navigation is simple 2D: scroll to zoom, middle-mouse drag to pan. Double-click a base, projected, section or detail view to open the Drawing View dialog, where you switch style (hidden edges, shaded), scale, tangent, interference and thread edges, and automatic center marks and center lines.
Tips and pitfalls#
Tip: Create the drawing last. Finish features, name components, set materials, and fill in properties before drawing, because the title block and parts list pull this data.
Tip: Keep a single design per drawing when possible. Multi-sheet drawings are fine, but several unrelated parts in one drawing document is awkward to update.
Warning: Dimensions in a drawing do not drive the model. Never "fix" a dimension by editing it in the drawing; edit the design.
Warning: A drawing is a separate file. If you share only the design (for example by exporting an F3D or STEP), the recipient does not get the drawing. Share drawings as PDF or DWG, or share the project.
Note: not confirmed in Autodesk's documentation: whether Personal-use or other license tiers limit any Drawing export format. The Drawing help does not mention license limits, so check Autodesk's current license comparison.
Worked example: from bracket to first sheet in numbers#
Use the practice bracket (100 x 60 x 8 mm plate, 6 mm holes, 20 mm slot). Choosing A4 landscape (297 x 210 mm) with an ISO template leaves a drawing area of roughly 277 x 190 mm once the border is subtracted, and the title block occupies the lower right. The plate is 100 mm wide, so at 1:1 the Front view takes about 100 x 60 mm, the Top view below it 100 x 8 mm, and there is ample room for dimensions. If you had chosen the same part at 2:1 the Front view would be 200 x 120 mm: it would still fit but leave no room for the Top view. This is the judgement the Base View dialog asks of you: scale first, sheet size second. As a rule, choose the largest standard scale (1:1, 2:1, 5:1, 1:2, 1:5) for which all views fit with at least 20 mm of clearance between them for dimension lines.
Base view placeholders and representations#
When the drawing is created from a template, the first views can come from placeholders defined in the template's own environment (Placeholder Views > Base View Placeholder on the Template toolbar). Autodesk's Placeholder View dialog lets you choose or create a reference, select a representation (Assembly, Component, Folded Component, Flat Pattern or Storyboard), set orientation, style and scale (Automatic by default), and set edge visibility (tangent, interference and thread edges). If the template uses placeholder views, they are used instead of the drawing-automation algorithm to place views.
An ordinary base view is different: its Representation is only Model (the static assembly) or Storyboard (an animation), and for sheet-metal components the Folded Model or Flat Pattern choice is made in the Create Drawing dialog. The reference, representation and orientation can be set only when the base view is first created.
Failure modes and fixes#
| Symptom | Likely cause | Fix |
|---|---|---|
| Get Latest button shown | Design saved a newer version | Click Get Latest, view each greyed-out sheet, then check for disassociated annotations |
| View is blank or shows the wrong part | Wrong contents or representation chosen at creation | Reference, representation and orientation cannot be changed on an existing base view; delete it and create a new one |
| Dimension text shows a very different number from last week | Model changed; the drawing is measuring | Check the model history; do not override text |
| Wrong standard discovered after dimensioning | Standard and units are read-only after creation | Recreate the drawing from the correct template or standard and re-place views |
| Title block fields blank | Properties empty on the design | Fill component properties and update |
| Drawing opens but can't find the model | Design moved, renamed or deleted | Restore it, then reopen the drawing |
| Sheet looks crowded | Scale too large | Edit the base view scale; dependent views follow |
Workflow advice#
Treat the drawing as the last stage of a release process. A reliable order is: finish the model; set the physical material; fill the part number, description and revision in properties; save a design version with a meaningful comment; create the drawing; place views; dimension; annotate; update and check; export. When revisions happen, change the model first, open the drawing, click Get Latest, and look for annotations flagged by the Annotation Monitor badge. Keep a one-line change note in the design version comment so the drawing's revision table can be filled in without guesswork.
If you work with a shop that expects specific conventions, send them a PDF of the first drawing early and ask what they would change. It is far cheaper to adjust a template after one drawing than after thirty.
Practice exercise#
- Model the bracket: a plate 100 x 60 x 8 mm with two 6 mm holes made with the Hole command and a 20 mm slot. Set the material to aluminum, fill in a part number and description, and save as "Bracket".
- Create a drawing from the design with ISO, mm and A4 landscape. Place a Front base view at 1:1 with visible edges.
- Add a Top projected view. Measure the clearance between the two views on the sheet and confirm it is at least 20 mm.
- Edit the base view scale to 2:1 and watch the dependent view move. Decide whether it still fits; if not, revert to 1:1 and write down the largest scale that fits.
- In the design, make the plate 120 mm long, save, return to the drawing and click Get Latest. Note which dimensions or views changed.
- Create a second drawing from the same design with the other standard (ASME, A size) and compare projection placement and title block layout.
- Expected result: two aligned views on an A4 sheet, a scale decision backed by measured clearances, evidence that the drawing follows model edits, and a side-by-side understanding of what the two standards change.
Related#
- Templates and standards (ISO/ASME)
- Base and projected views
- Dimensions and tolerances
- Export to PDF, DWG, and DXF